MOLDITQUICK

EDM for Mold Making — Sinker, Wire, Spark Gap and Recast Layer (2026)

RCRay Chan·2026-10-23·33 min read
Table of Contents

EDM for mold making is the process that decides whether a mold hits its target on the first tryout or the fourth. A sinker EDM burns geometry into steel that is already hardened to 48-52 HRC, with no cutting force, no tool deflection and no burr — which is why every deep rib, every sharp internal corner and every mirror cavity in a production tool was almost certainly cut by sparks rather than by a cutter.

The commercial consequence is simple. In a 25-30 day standard tool build, EDM typically occupies 3-8 working days of calendar but 10-20% of tool cost on a simple part and 30-40% on a deep-rib or heavily textured part. Buyers who understand spark gap, electrode wear and recast layer negotiate those numbers down; buyers who treat “EDM” as a single line item pay for electrode re-cuts and polishing that a parameter card would have avoided.

The Snapshot

  • ±0.005 mm is the fit tolerance wire EDM holds on insert blocks, ejector bores and shut-off faces; sinker EDM lands at ±0.01-0.02 mm on a cavity unless it is orbited and skimmed.
  • R0.1 mm is the minimum internal corner radius EDM reaches — roughly one thirtieth of the R3 mm corner a 6 mm end mill leaves behind, and the single biggest reason EDM exists in mold making.
  • 0.02-0.1 mm per side is the typical spark gap band from roughing to mirror finish; the electrode must be undersized by exactly twice that value.
  • 1-10 µm is the typical recast (white) layer after a proper skim sequence, against 15-25 µm when a cavity is finished in one high-current pass.
  • Ra 0.05-0.2 µm is mirror EDM; Ra 0.4-1.6 µm is normal mold finishing; wire EDM sits around Ra 0.1-0.4 µm with skim passes.
  • 4-9 minutes is the published single-part erosion cycle for axle, gear-shaft, flange and sprocket work on a production EDM cell — a reminder that the cycle is fast and the setup and electrode work are what cost.

Table of Contents

  1. The Snapshot
  2. What EDM does that milling cannot
  3. Sinker EDM vs wire EDM vs small-hole EDM
  4. Electrode material selection: graphite, copper and copper-tungsten
  5. Spark gap, overcut and electrode undersize
  6. Surface integrity: recast layer, heat-affected zone and micro-cracks
  7. Mold steels and components that EDM well
  8. Tolerances, Ra and metrology you can actually hold
  9. EDM in a 25-30 day mold build schedule
  10. EDM cost structure and what moves the price
  11. DFM rules for parts that will be EDM’d
  12. Troubleshooting common EDM defects
  13. How to audit an EDM and mold supplier
  14. Frequently Asked Questions
  15. Sources
  16. Start your EDM mold program

What EDM does that milling cannot

Milling is limited by three physical facts: the cutter has a diameter, the cutter has a length-to-diameter ratio, and the cutter has to push through the material. Each one shows up as a hard wall in mold work. A 6 mm ball-nose cutter cannot leave an internal corner sharper than R3 mm; a 3 mm cutter cannot reach deeper than roughly 12-18 mm before chatter and deflection ruin the wall; and a 50 HRC cavity will cut, but slowly enough that the machine hour bill exceeds what EDM would have charged.

Electrical discharge machining removes those walls because it never touches the workpiece. A shaped electrode advances into the cavity through a dielectric, and thousands of controlled sparks per second vaporise microscopic volumes of steel. There is no contact force, so hardness is irrelevant — any steel from 28 HRC pre-hardened P20 to 62 HRC D2 cuts at the same rate — and no deflection, so a 0.5 mm wide rib at 15:1 depth is a parameter decision rather than a machining miracle.

Capability CNC milling Sinker EDM Wire EDM
Minimum internal corner Tool radius (R1.5-R3 typical) R0.1 mm R0.05 mm on the wire path, but through-features only
Hardened steel above 45 HRC Slow, tool wear severe No limitation No limitation
Deep narrow rib ~4:1 depth-to-width, 8:1 with necked tools 10:1 practical, 20:1 with good flushing Not applicable
Blind 3D cavity Yes, with reach limits Yes — the core EDM job No
Through-slot in hardened plate Difficult, distortion risk Possible but slow Yes, ±0.005 mm
Surface finish as-cut Ra 0.8-3.2 µm Ra 0.05-1.6 µm Ra 0.1-0.4 µm
Burr Yes, needs deburring None None

CNC EDM for mold making versus milling only

CNC EDM for mold making is not a different machine — it is the same CAM environment driving a different cutter. The electrode solid and the orbit path are generated from the model that produced the milling toolpaths, so the cavity, the electrode and the inspection report share one datum scheme. That is what makes a ±0.01 mm cavity realistic: the error budget stays inside one model instead of accumulating across a manual electrode bench.

The same discipline explains why shops that cut CNC prototypes for a program usually keep the tooling in the same CAM file. CNC prototypes and mold inserts then come off one model, one shrink compensation and one tolerance stack, and the electrode geometry is a by-product of the part geometry rather than a re-modelled approximation of it. Our CNC machining service and EDM service run that combined path, which is the normal shape of a precision tooling supplier rather than an exception.

What EDM still cannot do

EDM is slow in absolute terms, it cannot produce a truly sharp external corner (the electrode wears), it leaves a thermally damaged surface layer that has to be planned for, and it needs a start hole or an open face for wire work. It also cannot fix a bad design: a 0.2 mm rib in a 300 mm tall core will burn, but the electrode will wear and break before the depth is reached.

Sinker EDM vs wire EDM vs small-hole EDM

The three EDM variants answer three different questions, and a mold shop that only owns one of them subcontracts the other two — which is where a week disappears from the schedule.

Variant Tool Dielectric Geometry Typical tolerance Typical Ra
Sinker (ram) EDM Shaped graphite or copper electrode Hydrocarbon oil Blind 3D cavity, ribs, textures, sharp internal corners ±0.01-0.02 mm (±0.005 mm orbited) Ra 0.4-1.6 µm, 0.05 µm mirror
Wire EDM Brass or coated wire, 0.1-0.3 mm Deionized water 2D profile through a plate, tapers, shut-offs, split lines ±0.002-0.005 mm Ra 0.1-0.4 µm
Small-hole EDM Brass tube electrode, 0.3-3 mm Water or oil Start holes, deep small holes, angled cooling lines ±0.02 mm Ra 1.6-3.2 µm

Sinker EDM is the mold maker’s core tool. It produces the cavity form, the deep ribs, the engraving and the textured surfaces, and it is the only process that can put a sharp internal corner in a hardened block. Modern sinker cells run mirror and double-ended configurations: mirror EDM uses low-current finishing with carefully matched electrode pairs to reach optical surface quality, and double-ended (dual-head) machines erode two electrodes in parallel to cut roughing time on multi-cavity tools.

Wire EDM is a two-axis (or four-axis tapered) process: the wire passes through the workpiece and cuts a profile. It is the correct answer for insert blocks, ejector pin holes, gate inserts, slide shut-offs, parting-line splits and any through-feature that must hold ±0.005 mm with parallel walls. It leaves no burr and exerts no force, so it can finish a 60 HRC plate that would distort under a cutter.

Small-hole EDM exists to serve the other two. Wire EDM needs a start hole, and a 0.5 mm hole in 50 HRC steel is not a drilling job. A tube electrode burns it in seconds, and the same head produces angled cooling-line holes and vent holes that a drill would wander through.

Decision rule in one line: blind 3D form goes to sinker, through-feature in hardened plate goes to wire, and the hole that lets the wire in goes to small-hole EDM.

Electrode material selection: graphite, copper and copper-tungsten

Electrode material sets removal rate, wear, achievable detail and electrode cost — and electrode cost is usually 15-30% of the EDM line in a tool quote. Choosing the wrong material is the most common self-inflicted cost in EDM.

Material Removal rate (roughing) Volumetric wear Detail limit Best for Cost index
Graphite (fine grain) 200-500 mm³/min 0.1-1% R0.2 mm, ribs 0.5 mm Bulk cavity roughing, deep ribs, high metal removal Low
Copper (electrolytic) 50-150 mm³/min 0.5-2% R0.05 mm, ribs 0.2 mm Fine finishing, sharp corners, mirror EDM Medium
Copper-tungsten (70/30, 80/20) 30-80 mm³/min under 0.5% R0.05 mm at depth Deep fine ribs, tight-tolerance finishing, carbide High

Graphite wins on speed and price. It is machined dry on a CNC mill at 3-5× the feed of copper, it weighs a fifth as much (a 300 mm electrode is handleable), and it roughs at currents a copper electrode would destroy itself at. Its weaknesses are edge chipping on very fine detail and the fact that it cannot be used in water-based dielectric.

Copper wins on detail. It holds a sharper edge, produces a better surface at low current, and is the standard choice for mirror EDM and for any cavity where the corner radius callout is R0.1 mm or tighter. It machines slower, weighs more and costs more per cavity, which is why shops rough with graphite and finish with copper on the same cavity.

Copper-tungsten is the answer when wear is the limiting factor rather than speed: deep, narrow ribs where a 1% wear allowance would break the tolerance, and any job involving carbide inserts. It is the most expensive of the three, typically several times the cost of graphite per electrode, and it is specified only where the geometry demands it.

Electrode wear and how many electrodes you actually need

Electrode wear is quoted as volumetric percentage in roughing and as linear (end or side) wear in finishing. The practical rule: a 1% linear wear on a 50 mm deep burn consumes 0.5 mm of electrode length, which is fine for the floor of a cavity and fatal for a dimension held to ±0.01 mm at the top edge. That is why a cavity is normally cut with one rough electrode plus one or two finish electrodes, and a mirror cavity with three to five, each stepped down in current rather than in size.

Ask for the electrode count in the quote. A supplier who quotes “EDM” as a single number either has not planned the wear sequence or is planning to polish the error out.

Spark gap, overcut and electrode undersize

The spark gap is the distance the electrode stands off the wall, and it is not a constant. It scales with current: a roughing pass at 40 A opens a gap of roughly 0.05-0.1 mm per side, a semi-finish at 10 A sits near 0.02-0.05 mm, and a mirror pass at 1-2 A closes to 0.005-0.02 mm.

That single fact drives the arithmetic every mold shop runs before cutting an electrode:

Electrode dimension = cavity dimension − (2 × spark gap per side)

A 10.00 mm slot cut with a 0.05 mm gap needs a 9.90 mm electrode. A 0.10 mm gap needs 9.80 mm. If the shop cuts the electrode to nominal, the cavity comes out 0.1-0.2 mm oversize and the insert is scrap.

Regime Current Gap per side Electrode undersize (per side) Achievable Ra Typical use
Rough 20-60 A 0.05-0.10 mm 0.05-0.10 mm Ra 3.2-6.3 µm Bulk removal, 0.5-2 mm stock
Semi-finish 8-20 A 0.03-0.05 mm 0.03-0.05 mm Ra 1.6-3.2 µm Step-down before finishing
Finish 3-8 A 0.02-0.03 mm 0.02-0.03 mm Ra 0.4-0.8 µm Cavity walls, ribs
Fine / mirror 0.5-3 A 0.005-0.02 mm 0.005-0.02 mm Ra 0.05-0.2 µm Optical and cosmetic surfaces

Orbiting changes the arithmetic

Orbital (planetary) EDM moves the electrode on a controlled XY path while it burns, which lets an undersized electrode produce a larger cavity, improves flushing at depth and gives the operator a second lever on size. With orbiting, the electrode is undersized by the gap plus the orbit radius, and the orbit radius becomes the finishing adjustment — a few microns of orbit replaces a re-cut electrode. This is how a shop holds ±0.005 mm on a sinker cavity without a new electrode for every correction.

Corner error is additive

At an internal corner the gap is radial, so the cavity corner radius equals the electrode corner radius plus the spark gap. An electrode cut to R0.05 mm with a 0.03 mm gap produces an R0.08 mm corner, not R0.05. If the print says R0.1 mm, the electrode has to be made sharper than the print — which is why electrode drawings carry their own corner callouts and why “R0.1 mm” is quoted as a capability, not a default.

Side walls also taper with depth on a single pass. Measure a deep cavity at the top and the bottom: a taper of more than 0.01 mm over 50 mm usually means flushing, not machine geometry, and the fix is through-spindle or through-electrode flushing rather than a second finishing pass.

Surface integrity: recast layer, heat-affected zone and micro-cracks

Every EDM surface is a thermally damaged surface. The spark melts a microscopic volume of steel; most of it is flushed away, and the remainder re-solidifies as a recast (white) layer — untempered, brittle, chemically different from the base metal and full of residual tensile stress. Beneath it sits a heat-affected zone where the original temper has been drawn back.

Condition Recast layer Heat-affected zone Risk
Single high-current roughing pass 15-25 µm 30-50 µm Micro-cracks at corners, poor polish response
Rough plus two skims 3-8 µm 10-25 µm Acceptable for most production tools
Fine finish with low current 1-3 µm 5-15 µm Good polish base, low crack risk
Mirror EDM sequence under 1 µm under 10 µm Optical polish achievable

Three consequences matter to a buyer:

Cracking on hardened steel. Recast on H13 or D2 above 45 HRC is where EDM-induced cracks start, and they start at internal corners where current density is highest. A tool that cracks after 20,000 shots usually has a 20 µm recast layer at a rib root, not a steel quality problem.

Loss of corrosion resistance on stainless molds. S136 (1.2083) relies on free chromium for its corrosion resistance. The recast layer is chromium-depleted, so an EDMed S136 cavity running PVC or a medical resin can corrode preferentially along the EDM surface. The fix is to polish the recast off, not to change the steel.

Polish response. Recast polishes at a different rate from the base metal, which shows up as a halo or “orange peel” ring around an EDMed detail after polishing. Mirror-grade cavities are therefore EDM’d with the finest practical sequence and then polished 0.02-0.05 mm deeper than the visible damage.

Control is procedural, not heroic: rough at high current for speed, then step current down through two to four skim passes so the final pass removes the damage the previous one created. On hardened steels above 45 HRC, heavy EDM should be followed by a stress-relief temper before the final finishing pass. For medical and PVC tooling, specify that recast is removed by polishing or electropolishing and that the requirement is verified on a coupon.

Verification is where suppliers get vague. Recast thickness is a metallographic measurement — a cross-section on a test coupon, read under a microscope with a micro-hardness traverse — not something a CMM or a roughness gauge can report. A credible supplier has a coupon procedure and can show a previous report. In production, the parameter card plus Ra plus a visual and penetrant check on critical corners is the normal control.

Mold steels and components that EDM well

Almost every mold steel EDMs, but they do not EDM equally. Carbon content, hardness and alloying set how much recast forms and how brittle it is.

Steel Hardness EDM behaviour Watch out for
P20 (1.2311) 28-34 HRC Fast, stable, low stress Recast is soft and gummy; polish after EDM
718H (1.2738) 33-38 HRC Fast, good finish Large plates need thermal stability time before final pass
H13 (1.2344) 44-52 HRC Cuts cleanly but recast is crack-prone Mandatory skim passes, temper after heavy EDM
S136 (1.2083) 48-52 HRC Excellent finish, mirror-capable Recast loses corrosion resistance — polish it off
NAK80 38-43 HRC Best polish response of the pre-hardened grades Lower toughness for heavy wear edges
D2 (1.2379) / S7 58-62 HRC Wire EDM preferred; sinker slow Cracking risk at sharp corners
Aluminum 7075-T6 150 HB Cuts very fast, low wear Built-up edge on electrode, poor detail below R0.3 mm

The pattern: pre-hardened grades (P20, 718H, NAK80) EDM fast and forgive a single-pass finish; through-hardened grades (H13, S136, D2) demand the skim sequence and, on S136, a polishing step for corrosion-critical work. That is why production tooling quotes H13 and S136 tools with more EDM and polishing time than a P20 tool of the same geometry.

Mold components that are normally EDM’d

A mold is not one cavity — it is a stack of plates and inserts, and EDM touches most of them. The component list below is the standard set a mold shop runs through its EDM cell.

Component EDM variant Why EDM Typical tolerance
Cavity plate Sinker Deep ribs, sharp corners, texture, engraving ±0.01-0.02 mm
Core plate Sinker + wire Core form, ejector bores, shut-offs ±0.01 mm form, ±0.005 mm bores
Slide cores Sinker + wire Angled forms, wear-plate seats ±0.01 mm
Inserts and gate blocks Wire Hardened block, precise pocket fit ±0.002-0.005 mm
Ejector pin holes Wire or small-hole Hardened plate, straight and parallel ±0.005 mm
Sprue bush bore Sinker or wire Hardened, concentric with nozzle seat ±0.01 mm
Guide pin and bush bores Wire Alignment bores in hardened plates ±0.005 mm
Return pins, support pillars Wire / small-hole Through-holes in hardened plate ±0.01 mm
Top plate, bottom plate, locating ring Wire / small-hole Bolt patterns, sprue clearance, locating features ±0.02 mm
Parting-line shut-offs Wire Zero-flash fit between cavity and core ±0.005 mm

Ejector holes are the quiet cost centre. A 32-cavity tool has 60-100 ejector bores, all of which must be straight, parallel and within ±0.005 mm, or pins bind and gall within the first thousand shots. That work is wire EDM, and it is why wire capacity — not sinker capacity — is the usual bottleneck in a high-cavity build.

Tolerances, Ra and metrology you can actually hold

EDM tolerances are frequently over-promised because the number quoted is the machine’s positioning resolution rather than the process capability. The honest bands:

Feature Process Realistic tolerance Realistic Ra
Insert pocket and block fit Wire EDM ±0.002-0.005 mm Ra 0.1-0.4 µm
Ejector and guide bores Wire EDM ±0.005 mm Ra 0.2-0.4 µm
Parting-line shut-off Wire EDM ±0.005 mm Ra 0.2-0.4 µm
Cavity form, small Sinker EDM ±0.01 mm Ra 0.4-0.8 µm
Cavity form, orbited and skimmed Sinker EDM ±0.005-0.01 mm Ra 0.2-0.4 µm
Deep rib width Sinker EDM ±0.01-0.02 mm Ra 0.4-1.6 µm
Mirror cosmetic surface Sinker EDM ±0.005-0.01 mm Ra 0.05-0.2 µm
Start hole position Small-hole EDM ±0.02 mm Ra 1.6-3.2 µm

Two honesty checks belong in every EDM conversation. First, size matters: ±0.005 mm is a small-feature, short-distance number. Across a 500 mm plate, thermal growth and machine geometry push the realistic figure to ±0.01 mm, and a supplier who promises ±0.005 mm over half a metre without a temperature-controlled room is quoting hope.

Second, the gauge has to be four times better than the tolerance. Verifying ±0.005 mm needs a CMM with a stated uncertainty around ±0.0015 mm, measured at 20 °C, with the measurement report showing the uncertainty. Calipers and pin gauges confirm a hole exists; they do not confirm a tolerance. The part-side budget that sits on top of these mold numbers is covered in the injection molding tolerances guide.

Metrology for EDM work is a short list, and all of it should appear in the first-article report:

  • CMM for position, profile and GD&T callouts defined per ISO 1101 — the standard that governs how a true-position or profile tolerance is interpreted on the mold drawing.
  • Roughness tester reporting Ra and Rz per ISO 21920-2, which replaced the older ISO 4287 parameter set. Specify which parameter and which cut-off, or the number is not comparable.
  • Pin and plug gauges for bore size at the top and bottom of a through-hole, which is how taper is caught.
  • Profile projector or vision system for electrode verification before the burn, not after.
  • Penetrant inspection on critical corners of hardened cavities, to catch EDM micro-cracks before tryout.

Our quality control flow puts the first-article CMM report and the roughness data in the same package as the material certificates, which is what an IATF 16949 program expects to see.

EDM in a 25-30 day mold build schedule

EDM is rarely the longest stage in a tool build, but it is almost always the stage that absorbs delays from everywhere else. The standard production-tool calendar looks like this:

Stage Working days EDM involvement
DFM and mold design 1-3 Electrode strategy and EDM-vs-milling decision fixed here
Steel procurement 2-5 —
Rough CNC milling 3-7 Start holes burned where wire access is needed
Stress relief / heat treatment 3-7 Hardened steels only; pre-hardened grades skip it
Finish CNC milling 3-5 Leaves 0.2-0.5 mm stock on EDM surfaces
Sinker EDM 3-6 Cavity forms, ribs, engraving, texture
Wire EDM 2-4 Inserts, ejector bores, shut-offs, splits
Polishing and texturing 2-5 Removes recast, sets final gloss
Assembly, spotting, fitting 2-4 Shut-off blue-check, slide fit
Tryout T0/T1 and sample approval 3-5 EDM corrections if steel needs adjustment

The stage list adds to more than 25 days because the good shops run it in parallel: wire EDM on inserts starts while the cavity is still on the sinker, and polishing starts on finished surfaces while the rest of the cavity is still burning. A 25-30 day standard build and 45 days for automotive-grade tooling are achievable only when EDM capacity is not shared across too many concurrent tools.

Three schedule facts determine whether your tool lands on day 26 or day 40:

Electrode count is a schedule risk. A cavity needing six electrodes needs six electrode blanks, six CNC milling slots and six inspection steps. A 5-axis mill that reaches the geometry directly can remove two of those electrodes and four days.

Wire EDM is the bottleneck, not sinker. High-cavity tools generate hundreds of ejector and guide bores. If the supplier’s wire capacity is two machines and they are running eight tools, your ejector work queues behind seven other tools.

EDM after heat treatment is unavoidable on H13 and S136. Hardening distorts a cavity by 0.05-0.2 mm, which must be removed by finishing, and that finishing is EDM plus polishing. Pre-hardened P20 avoids the heat-treat step entirely, which is a real three-to-seven-day saving on a Class 103 tool.

Real programs show the same pattern from the buyer side. A 150-plus mold-set audio program ran on an 8-week cadence per model with ±0.05 mm mold steel accuracy; a VR front cover tool hit ±0.02 mm mold accuracy inside a 6-week rapid tooling window; a 32-cavity button tool at 5M units/year took 12 weeks to a ±0.03 mm part; and an automotive connector tool at ±0.005 mm critical tolerance took 10 weeks. In every case the EDM and polishing tail after heat treatment was the stage with the least float.

EDM cost structure and what moves the price

EDM for mold making is quoted three ways: an hourly rate, a per-cavity estimate, or a percentage of tool cost. All three are defensible, and all three hide the same drivers.

Cost element Typical band What drives it
Sinker machine time $35-90 per hour (North America and Europe shop rates) Current regime, flushed area, number of electrodes
Wire machine time $45-120 per hour Plate thickness, number of skim passes, bore count
Graphite electrode $20-150 each Size, fine-grain grade, rib detail
Copper electrode $40-250 each Size, detail, mirror-finish requirement
Copper-tungsten electrode $150-600 each Deep fine-rib geometry only
Electrode CNC milling $30-120 per electrode Detail level, number of electrodes
EDM share of tool cost 10-20% simple, 30-40% deep-rib or textured Geometry and finish spec
Post-EDM polishing $500-10,000 per tool Recast removal, SPI/VDI grade, cavity count

Four design decisions move the EDM number more than any negotiation:

  1. Rib depth ratio. Going from 8:1 to 15:1 typically doubles electrode count and lengthens burn time sharply, because flushing degrades and wear forces extra finishing electrodes.
  2. Corner radius callout. A part corner at R0.2 mm instead of R0.1 mm can let a smaller cutter pre-machine more of the form, and reduces the number of ultra-fine electrodes.
  3. Mirror versus fine finish. Ra 0.05 µm is a multi-electrode, multi-pass sequence that typically takes two to three times the burn hours of a Ra 0.4 µm finish; Ra 0.4 µm is a two-electrode sequence.
  4. Texture route. EDM-applied texture is per-cavity machine time; acid-etch texture is a batch process after polishing. On multi-cavity tools, etching is usually cheaper, but it removes 0.02-0.05 mm of steel and needs extra draft — see the surface finishing options before locking the texture spec.

The injection molding cost guide covers how the tool cost then amortises into part price; the EDM line is where most of the cost difference between a simple cavity tool and a deep-rib tool sits.

DFM rules for parts that will be EDM’d

Design decisions made on the part model set the EDM bill before a supplier is even chosen. These are the rules that matter.

Internal corner radii. Specify R0.15-0.3 mm where the design allows, and reserve R0.1 mm for features that truly need it. A sharp internal corner in the part is an external corner on the core, which is where electrodes wear fastest and where recast concentrates.

Rib depth to width. EDM handles 10:1 comfortably and 20:1 with through-electrode flushing; milling handles about 4:1. A 0.8 mm rib at 8 mm depth is an EDM feature by definition, and the electrode will be copper or copper-tungsten, not graphite.

Wall thickness. 0.5-3 mm is the mouldable band; below 0.5 mm the EDM gap becomes a significant fraction of the wall and tolerance stack gets ugly.

Draft. 0.5-2° per side on smooth faces, 3° or more on textured faces. Textured walls need extra draft because the texture depth itself resists ejection — deep VDI textures commonly need 4-5°.

Texture specification. VDI 3400 grades map to Ra values: grade 24 is about Ra 1.6 µm, grade 30 about Ra 3.15 µm, grade 33 about Ra 4.5 µm, and grade 45 around Ra 18 µm. Specify the grade, the Ra, and the process route (EDM texture or acid etch), because the same grade achieved two ways has different draft and different cost. Photograph or sample-approve the texture; a number alone does not survive a cosmetic review.

Tolerance callouts. Use a general tolerance block per ISO 2768-m for non-critical features and reserve ISO 1101 GD&T for the 5-10 features that actually control fit and function. A drawing with ±0.01 mm on every dimension multiplies EDM and inspection time for no functional gain.

Undercuts and side actions. Every undercut adds a slide, and every slide adds EDM’d wear-plate seats and shut-offs. If a design change can remove a slide, it also removes a seat, a shut-off and a fitting operation from the quote.

Deliver a STEP model and a 2D drawing. EDM electrode geometry is generated from the solid; the tolerance and texture intent lives on the drawing. Sending one without the other is the most common cause of a first-article surprise.

Troubleshooting common EDM defects

Most EDM defects are diagnosable from the symptom, and most are parameter or flushing problems rather than machine faults. The table below is the version worth carrying into a supplier review.

Symptom Likely cause Corrective action
Thick white layer, cracks at corners Single high-current pass, no skims Add 2-4 skim passes stepping current down
Taper or barrel in a deep cavity Poor flushing, electrode wear at the tip Through-electrode flushing, orbit, re-dress electrode
Black spots and arc damage Debris in the gap, insufficient jump Increase jump height, check filter, raise off-time
Carbon or copper build-up on the cavity Wrong polarity or low open-circuit voltage Verify polarity for the electrode material, raise voltage
Pitting on a mirror surface Contaminated dielectric Change filter, clean tank, settle time before finishing
Cavity oversize by 0.05-0.2 mm Gap not compensated, electrode at nominal Re-measure electrode, apply wear offset, orbit correction
Corner washout on ribs Current density too high at a thin section Reduce current at corners, use corner orbit control
Wire breakage on thick sections Flushing pressure, tension, current Lower current, raise flush pressure, check wire tension
Dimension drift after EDM Residual stress relaxing after the burn Stress-relieve before final pass, finish after thermal soak
Texture inconsistent across cavities Different electrode wear per cavity One electrode per cavity for textured work, or index electrodes

The pattern is consistent: flushing and current discipline cause most defects, and both are visible in the parameter card. Ask to see the card for a cavity comparable to yours — current per pass, on/off time, jump height, flush pressure, electrode count, and the wear offset applied. A shop that cannot produce the card is running on operator feel, which does not repeat across cavities or across programs.

How to audit an EDM and mold supplier

An EDM audit is mostly a capacity and documentation audit. Machines are visible; discipline is not, so ask for the artefacts.

  1. Machine inventory with generation and axes. Sinker count, wire count, whether the sinkers have orbital and mirror capability, whether the wires run 0.1 mm wire, and the largest workpiece each can take. Four sinkers and two wires is a different shop from two sinkers and six wires.
  2. In-house electrode milling. Graphite milling with dust extraction and a CMM for electrode verification. Subcontracted electrodes add two days and a tolerance hand-off per iteration.
  3. EDM parameter cards per cavity. Current per pass, skim sequence, orbit, wear offset. This is the single best predictor of repeatability.
  4. Recast control procedure. A coupon cross-section method, a micro-hardness check, and a defined polishing allowance after EDM on hardened steels.
  5. Metrology. CMM with a stated uncertainty, roughness tester reporting per ISO 21920-2, and first-article reports that show GD&T results per ISO 1101 rather than a list of nominal dimensions.
  6. Wire capacity against concurrent tools. Ask how many tools are in EDM at once and how many wire machines serve them. This is where a 30-day promise quietly becomes 45.
  7. Certification and documentation. IATF 16949 or ISO 9001 as a baseline, with PPAP/FAI available for automotive programs and material certificates for every steel lot.
  8. Texture and polishing partner. Whether texture is EDM-applied or acid-etched, and who approves the sample. Texture disputes are the most common late-stage argument on cosmetic tools.

We deliver EDM and mold work through our qualified tooling network, backed by an IATF 16949 and ISO 9001 certified quality system, with wire EDM and sinker capacity quoted as part of the tool build rather than as extras. The mold making service page covers the full chain, and the mold maker selection guide covers the commercial side of the same audit.

Frequently Asked Questions

What is EDM for mold making used for?

Sinker EDM cuts the cavity form, deep ribs, sharp internal corners, engraving and texture into hardened steel; wire EDM cuts insert pockets, ejector bores and parting-line shut-offs to ±0.005 mm. On a hardened production tool, the cavity form, the rib roots, the insert pockets, the ejector bores and the shut-offs all pass through an EDM cell at some point.

Can EDM cut steel that is already hardened?

Yes — that is its main advantage. EDM cuts any hardness from 28 HRC to 62 HRC at the same rate because it removes material thermally rather than mechanically. This is why hardened H13 and S136 tools are EDM’d after heat treatment instead of being machined soft and then hardened.

What is the difference between sinker EDM and wire EDM?

Sinker EDM pushes a shaped electrode into a blind 3D cavity through oil dielectric. Wire EDM passes a brass wire through a plate in water and cuts a 2D profile. Sinker holds ±0.01-0.02 mm on cavity form; wire holds ±0.002-0.005 mm on through-features.

What is spark gap in EDM?

Spark gap is the standoff between electrode and workpiece, typically 0.02-0.1 mm per side depending on current. The electrode must be undersized by twice the gap, so a 10.00 mm slot cut with a 0.05 mm gap needs a 9.90 mm electrode.

What is a recast layer and why does it matter?

Recast is the resolidified steel left on an EDM surface, typically 1-10 µm after a proper skim sequence and 15-25 µm after a single high-current pass. It is brittle, crack-prone and, on stainless mold steel, chromium-depleted — so it is removed by skimming, polishing or stress relief depending on the application.

How thick is the white layer after EDM?

On a finishing regime, 1-3 µm; on roughing at 40-60 A, 15-25 µm with a heat-affected zone of 30-50 µm beneath it. Anything above roughly 10 µm on a 48 HRC cavity warrants penetrant inspection at corners.

Which electrode material should be specified?

Graphite for roughing and bulk removal (200-500 mm³/min, low cost), copper for fine detail and mirror finishing (R0.05 mm capability), copper-tungsten for deep fine ribs where wear must stay under 0.5%. Most cavities use graphite to rough and copper to finish.

What tolerance can EDM hold?

Wire EDM holds ±0.002-0.005 mm on small features and ±0.01 mm across a 500 mm plate. Sinker EDM holds ±0.01-0.02 mm on cavity form, tightening to ±0.005 mm with orbiting and skim passes. Larger parts and uncontrolled shop temperature widen both numbers.

What surface finish can EDM achieve?

Standard mold finishing lands at Ra 0.4-1.6 µm, fine finishing at Ra 0.2-0.4 µm, and mirror EDM at Ra 0.05-0.2 µm. Wire EDM typically produces Ra 0.1-0.4 µm with skim passes, depending on plate thickness and wire diameter.

How much does EDM add to a mold cost?

EDM is usually 10-20% of tool cost on a simple cavity and 30-40% on a deep-rib or heavily textured tool. Machine time runs $35-90 per hour for sinker and $45-120 per hour for wire in North American and European shops, plus electrodes at $20-600 each.

How long does EDM take in a mold build?

Sinker EDM typically occupies 3-6 working days and wire EDM 2-4 days inside a 25-30 day standard tool build, running in parallel with polishing and assembly. Automotive-grade builds at 45 days carry more EDM and more inspection, not slower machines.

Does EDM leave the mold weaker?

The base metal is unaffected beyond 10-50 µm, so a properly skimmed cavity is as strong as its steel. The risk is unskimmed recast at sharp corners on hard steels, which is why EDM parameter discipline and a post-EDM temper matter more than the process itself.

Can EDM create texture instead of acid etching?

Yes. EDM-applied texture reproduces a VDI 3400 grade directly in the cavity — grade 24 is about Ra 1.6 µm, grade 30 about Ra 3.15 µm — without the 0.02-0.05 mm of stock removal that acid etching takes. Etching is usually cheaper on multi-cavity tools; EDM texture is better for single cavities and for re-texturing a repaired area.

Can EDM work on aluminum rapid tooling?

Yes, and it cuts fast with low electrode wear, but detail below R0.3 mm is unreliable because aluminum tends to build up on the electrode. Aluminum tools are usually milled, with EDM reserved for sharp corners and deep ribs.

Sources

Start your EDM mold program

Send the part model, the steel you intend to use and the features that actually control fit, and we will quote the EDM scope explicitly — electrode count, sinker hours, wire hours, polishing allowance and the recast control procedure — inside a 25-30 day build (45 days for automotive-grade). We deliver that work through our qualified tooling network under an IATF 16949 and ISO 9001 certified quality system, with CMM first-article data and roughness reports per ISO 21920-2.

Get a quote or talk to an engineer about the corner radii, rib depths and texture grade before the design freezes — those three decisions move the EDM line more than any negotiation after the PO.

NEXT STEP

Ready to Start Your Project?

Send us your requirements — our team responds within 24 hours. Pricing and a realistic lead time come with the reply.

RC

Written by

Ray Chan

Export Brand Manager · Injection Molding, Mold Making & DFM. Ray helps global importers and integrators source factory-direct plastic parts and tooling.

← Back to Blog